Welcome to MCAD Central

Join our MCAD Central community forums, the largest resource for MCAD (Mechanical Computer-Aided Design) professionals, including files, forums, jobs, articles, calendar, and more.

Register Log in

How to extract CUTTING TIME in Pro/NC

dida128

New member
I need something what most people working with Pro/NC need.

It is automatic creation of some kind of parameter in NC-SEQUENCE which will contain CUTTING TIME what Pro/NC gives in info for NC-SEQUENCE or in .ppl file.

Please be so kind and give me some ideas.

I tryed everything, but nothing I am capable to do works.



THNX

dida128
 

gunther

New member
This cannot be done automatically in Pro/ENGINEER. THe cutting time can be retrieved from Manufacturing Info, or from GPOST, whichever is more accurate, and entered manually based on that. The cutting time from GPOST has the potential to be more accurate, anyway, depending upon the construction of the post.



I have submitted an enhancement request for this, and I know some of my colleagues have as well.
 

adicar01

New member
yes, like gunther says, the cutting time it's depedent of machine set-up, not NC-Sequence.

and ths is depends wich post you are use:

-gpost, or

-ncpost

if you use gpost and vericut for verifier, verycut it's prety good for time optimization

[email protected]
 

appinmi

New member
Try creating, or adding this to your "tool change" sectionin G-post. This will give you cycle times for each tool and output them to the tape code.


CIMFIL/ON,LOADTL


RSLT=POSTF(20) $$ SAVE CURRENT CL RECORD


TIME=TEXT/POSTF(1,3,0498) $$ GET CYCLE TIME BETWEEN TOOL CHANGES


INSERT/'(TOOL CYCLE TIME=',TIME,')',EOB $$ EOB IS"END OF BLOCK" CHARACTER


RSLT=POSTF(21) $$ RETRIEVE CURRENT CL RECORD


RSLT=POSTF(13)$$ PROCESS CURRENT CL RECORD


CIMFIL/OFF


You can also get "total time" by looking at the "lst" file generated by G-post
 

peterbrown77

New member
This has been addressed in Wildfire M180 and newer. There is a new parameter which can be added to the sequence sheet's repeat region


mfg.oper.ncseq.cutting_time


Regards
 

the_real_jat

New member
you can try this.. i am not sure how u have to fix it.. but this macro is good for any machine.... it writes program size and machining time..


ENDSUM=MACRO


_TTIME=POSTF(1,3,495)&nb sp; $$ DBLCOM 495:total machining time


_TCHAR=POSTF(1,3,494)&nb sp; $$ DBLCOL 494:total tape length


PPRINT/'CYCLE TIME:',_TTIME,'sec. BYTES:',_TCHAR


TERMAC


now to print the machining time at the end of the program we need to make a CIMFIL macro on FINI.


CIMFIL/ON,FINI


%SAVE_CLREC


CALL/ENDSUM


%RESTORE_CLREC


%PROCESS_CLREC


CIMFIL/OFF





i have this helps
 

marker4x4

New member
peterbrown77 said:
This has been addressed in Wildfire M180 and newer. There is a new parameter which can be added to the sequence sheet's repeat region


mfg.oper.ncseq.cutting_time




Can't see it in WF3 (M020) ???? Can anyone confirm that please.

Thanks,
 

Sponsor

Top