Join our MCAD Central community forums, the largest resource for MCAD (Mechanical Computer-Aided Design) professionals, including files, forums, jobs, articles, calendar, and more.
Your request doesn't explain your circumstances. There are several ways to create layers. I'm probably overlooking a few, but here are five.
<LI>Createtemplates (part, assembly, sheet metal, etc)and manually create the layers complete with rulesfor adding default entity types to the appropriate layers. This is time consuming andshould only be done when initially creating company standard modeling templates.</LI>
<LI>Manually create the desired layers using the config.pro option shown above in ankarl's reply. This will create the layers if that entity type is created in the model. For example, if you create an axis, the axis layer will be created. If you never created an axis in your model, the axis layer won't be created. </LI>
<LI>Layers from an existing model can be saved to a file and retrieved into another model. Automatically create the list from an existing model with layers by selecting "Settings > Setup File > Save. It will save them to a config.pro file for you. Alternatively you can import these layers by opening a config.pro file containing these layer options. You might want to name it layers.pro if you intend to use it this way. This option is great if you are only copying the layers from an existing template once or twice.</LI>
<LI>ModelCHECK can be configured to verify and create if necessary the default layers. I use it to standardize models received from other sources outside my company. ModelCHECK isn't worth the configuration effort to modify one or two files. But it is definitely worth the effort when you receive several files every week.</LI>
<LI>When importing IGES and STEP files, there is a config.pro option to use the default template model. Your template should already have your standard layers defined. Pro/ENGINEER will copy your company model template and insert the imported geometry at the end of the model tree. The option is "intf_in_use_template_models" yes/no.</LI>
When importing IGES and STEP files, there is a config.pro option to use the default template model.Pro/ENGINEER will copy your company model template and insert the imported geometry at the end of the model tree. The option is "intf_in_use_template_models" yes/no.
And it works fine! Added it to our company config.pro. How many timesdidn't Itell my colleguesFIRST to create a part and THEN import the received geometry. No need for that any more now. Thanks!
There was one problem with this option - When exporting data into a part with features already in it, you don't get the option to select a coordinate system.Pro/E just dumps the data onto your default csys.Ittook me awhile to figure out what was going on so proceed with caution.
This site uses cookies to help personalise content, tailor your experience and to keep you logged in if you register.
By continuing to use this site, you are consenting to our use of cookies.
