Subroutines in macro style

[PJ007B]

Just wanted to see if anyone has tryed to
change their code output on subroutines to use macros.
We would like to change our 4 axis mill post to handle this.Thanks for looking

This is an example of what were looking for.
Drill 6 holes around od of part.
( 0.196 DRILL)
T5
M6
#100=6(NO HOLES)
#1=60(INDEX)
#2=1(COUNT)
#3=.0(START POS)
G90G0G98G56
X-.293Y0.A#3
S1200M3
G43Z1.H5T20M8
WHILE[#2LE#100]DO1
G73X-.293Y.0A#3Z-.6R0.1Q.06F3.
G80
#2=#2+1
#3=#3+#1
END1(END OF SUB)
G91G28Z0M9
G28Y0M5
M1

 

[jcrook]

Hi PJ,
I do something similar with a regular lathe program. We also have many macros that we call that could be considered sub-programs or routines. This example does not have the DO loop, but could be written if we wanted to cut multiple spacers from a tube without bar pulling part everytime.


O3001( SPACER/WASHER )


( COLLET - " DIA, STICK BAR OUT " FROM COLLET )


( TOOL #1 OFFSET #1 BAR PULLER )
( TOOL #2 OFFSET #2, 80 DEG TOOL HOLDER MCLNR-164D, )
(* .030 RAD INSERT CNMG 432 )
( TOOL #3 OFFSET #3, 3/4" SPOT DRILL )
( TOOL #8 OFFSET #8, DRILL DIAM., DEPTH )
( TOOL #12 OFFSET #12, CUTOFF TOOL, ANY INSERT )


#501= .625 (MATERIAL DIAMETER)
#502= .14 (SPOT DRILL POINT DEPTH)
#503= 1.0 (DRILL POINT DEPTH)
#504= .375 (DRILL DIAMETER)
#505= .375 (LENGTH OF PART)


( FACE & TURN )
G0G20G40G97G99
T0202
G97S2268M3
/G1X8.0Z-0.05F0.1323
G0X8.0Z-0.05M8
G50S3500
G96S520
G0X[#501+.1]
G1X[#501+.002]F.007
G2U-.1W0.05R.05F.005
G1X-0.07F.007
G0Z0.1M9
G0X8.0Z8.0
/G28U0W0M9
M1
( 3/4" SPOT DRILL )
G65P9010A#502B.75F.003S700T0303
G0X0.0Z7.0M9
/G28U0W0M9
M1
( " DRILL " DIAM.)
G65P9010A#503B#504F.006S407T0808
G0X8.0Z5.0M9
/G28U0W0M9
M1
( CUTOFF & BAR PULLER )
G65P9030A#505B#501R.04S325X.3V1.0E.03U1.0
G0X10.0Z4.0M9
/G28U0W0M9
M1
M54
M99



Jay.