BOM QTY

[rthannaby]

Is there a way to alter the qty that the BOM shows? In other words I would like to be able to insert 1 fastener but have the BOM show 100. Somebody here suggested inserting 1 and pattering it 100 times with 0 displacement. Does anyone have any other ideas?


Thanks in advance

 

[doronron1]

Add table relation:-
IF asm_mbr_name == "your drawing number"
qty = "AR"
ELSE
qty = rpt_qty
ENDIF


That was the easy part. After closing the editor and saving your code,
Pro/E will complain right away if something is amiss. If all is well, go
back to Repeat Regions and select Switch Syms to change the display of the
table's contents from the parts list to the repeat regions driving the
table. Then choose Table, Enter Text, Report Sym, and select the cell
containing the quantity repeat region (usually the top right cell). Then
select "rpt", "rel", and User Defined, at which point you will enter "qty"
in the text field at the command line. This entry is not case sensitive.
"Done" your way out of that and switch the symbols back to text. You should
see an "AR" pop into the table somewhere.

 

[frankovijw]

You can also "Insert - component - include" which will add the extra pieces into the BOM, but not have the geometry in the model. I kind of like the table relation approach for your needs, but this could also work.

 

[tomwalls]

I have another alternative which we use here.

In your quantity column, use a parameter called "bomqty" instead of "rpt_qty".
Add a parameter to your assembly model(s) called "quantity" and set its initial value to be "X".

Add this relation to your repeat region:

if asm_mbr_quantity !="X"
bomqty=asm_mbr_quantity
else
bomqty=rpt_qty
endif

If you do nothing, it will default to the actual quantity in the assembly. If you want to override the actual quantity, you can edit the value of asm_member_quantity from "X" to whatever you need to show in the table.