creating corner point on fillet for dim.

[s_pme20]

Hello Friends,
I can not get red line (see below image) in pro-E dwg.
It should move with view and change with change in view scale.

View attachment 5191

Thanks.

 

[snufflufikist]

I have had this same issue and am seeking a solution.

Though in my case, I am usually looking to show the centre. How can you show the "crosshairs" for the centre point?


Edited by: snufflufikist

 

[contour]

Sketch>Sketcher Preferences... Check Mark in Parametric sketching and Chain sketching.


Sketch>Line... in Snapping References select edges, witchneed to be elongated, as references> Sketch lines.


To show the centre: If surface has centre, axis can be created. Create axis in model and show it in drawing.

 

[snufflufikist]

Thanks again Contour.

 

[s_pme20]

..looks like a long way...there should be some functionality during dim. creation for this!!!

By the way thanks Contour..

 

[sjoaosilva]

Hello,
two options:
First: In part you can create an axis in the intersection
of the two surfaces,then in the drawing show/erase axis.
second: chose intersection option to place one of the points of the
dimention.View attachment 5200

 

[timmy]

Also note when you create this dimension using intersection, you can go to the display tab in theproperties of that dimension and check "enable intersection witness lines". Thiswill show where the intersection is derived from.

 

[contour]

This is very interesting, Timmy. Unfortunately I can not find "display tab in theproperties of that dimension". Where is it?

 

[Tim.0666]

In Creo 5.0, after the dimension is created, rmb 'properties' the center tab is the 'display' tab. Towards the bottom of the box is the check box for 'enable intersection witness lines'


View attachment 5204

 

[contour]

Thanks. Fortunately, I still not have Creo

 

[s_pme20]

i am also on WF 4

BTW its nice that they added it in creo..!!
Thanks all..

 

[Roger]

Just curious, how do you plan on measuring a non-existant corner?


Suggestion: Locate the hole and then locate the angled surface from the hole, normal to the surface,to include the angular dimension.

 

[SRINIVASANIYER1]

If it is only to dimension, you can select the first point as the intersection of the two edges. As for the lines, you can sketch them. Alternatively, you can sketch a point.
IMP!!!, select all the sketches, RMB "relate to view" and then select the view to which they should be related.


View attachment 5211


View attachment 5212

 

[SRINIVASANIYER1]

Just curious, how do you plan on measuring a non-existant corner?

The only way I know is to create an axis at the intersection of the two surfaces and measure between them.

 

[dr_gallup]

Just curious, how do you plan on measuring a non-existant corner?

There are lots of things dimensioned and measured to nonexistent sharp corners. You measure it just like you draw it by projecting straight lines and finding their intersection. This is frequently done on an optical comparator. Not saying it's the best way to do something, but it is done in industry all the time.

 

[Bell]

Using draft fillet is one of the option in WF 4 and
previous versions. From WF5 "show intersection witness
line" is available in drawing properties window. Refer the
link.

http://www.beyondmech.com/pro-e/cad-topic-19.html

 

[Roger]

I repeat; where is it, really?

 

[huhj]

for Core 2.0 also need to change 'witness_line_offset' valve to small one, the shown corner = length of the intersection witness line -witness line offset. more detail. plese check Creo Help 'About Displaying intersection witness lines'

 

[design-engine]

I think he meant WF5 not creo 5.0